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Revar Desmera edited this page Nov 29, 2024 · 1 revision

Attachments Tutorial

Attachables

BOSL2 introduces the concept of attachables. You can do the following things with attachable shapes:

  • Control where the shape appears and how it is oriented by anchoring and specifying orientation and spin
  • Position or attach shapes relative to parent objects
  • Tag objects and then control boolean operations based on their tags.
  • Change the color of objects so that child objects are different colors than their parents

The various attachment features may seem complex at first, but attachability is one of the most important features of the BOSL2 library. It enables you to position objects relative to other objects in your model instead of having to keep track of absolute positions. It makes models simpler, more intuitive, and easier to maintain.

Almost all objects defined by BOSL2 are attachable. In addition, BOSL2 overrides the built-in definitions for cube(), cylinder(), sphere(), square(), circle() and text() and makes them attachable as well. However, some basic OpenSCAD built-in definitions are not attachable and will not work with the features described in this tutorial. The non-attachables are polyhedron(), linear_extrude(), rotate_extrude(), surface(), projection() and polygon(). Some of these have attachable alternatives: vnf_polyhedron(), linear_sweep(), rotate_sweep(), and region().

Anchoring

Anchoring allows you to align a specified part of an object or point on an object with the origin. The alignment point can be the center of a side, the center of an edge, a corner, or some other distinguished point on the object. This is done by passing a vector or text string into the anchor= argument. For roughly cubical or prismoidal shapes, that vector points in the general direction of the side, edge, or corner that will be aligned to. For example, a vector of [1,0,-1] refers to the lower-right edge of the shape. Each vector component should be -1, 0, or 1:

include <BOSL2/std.scad>
// Anchor at upper-front-left corner
cube([40,30,50], anchor=[-1,-1,1]);

Figure 1

include <BOSL2/std.scad>
// Anchor at upper-right edge
cube([40,30,50], anchor=[1,0,1]);

Figure 2

include <BOSL2/std.scad>
// Anchor at bottom face
cube([40,30,50], anchor=[0,0,-1]);

Figure 3

Since manually written vectors are not very intuitive, BOSL2 defines some standard directional vector constants that can be added together:

Constant Direction Value
LEFT X- [-1, 0, 0]
RIGHT X+ [ 1, 0, 0]
FRONT/FORWARD/FWD Y− [ 0, −1, 0]
BACK Y+ [ 0, 1, 0]
BOTTOM/BOT/DOWN Z− (Y− in 2D) [ 0, 0, −1] ([0, −1] in 2D.)
TOP/UP Z+ (Y+ in 2D) [ 0, 0, 1] ([0, 1] in 2D.)
CENTER/CTR Centered [ 0, 0, 0]

If you want a vector pointing towards the bottom−left edge, just add the BOTTOM and LEFT vector constants together like BOTTOM + LEFT. This will result in a vector of [−1,0,−1]. You can pass that to the anchor= argument for a clearly understandable anchoring:

include <BOSL2/std.scad>
cube([40,30,50], anchor=BACK+TOP);

Figure 4

include <BOSL2/std.scad>
cube([40,30,50], anchor=FRONT);

Figure 5

For cylindrical type attachables, the Z component of the vector will be −1, 0, or 1, referring to the bottom rim, the middle side, or the top rim of the cylindrical or conical shape. The X and Y components can be any value, pointing towards the circular perimeter of the cone. These combined let you point at any place on the bottom or top rims, or at an arbitrary side wall.

include <BOSL2/std.scad>
cylinder(r1=25, r2=15, h=60, anchor=TOP+LEFT);

Figure 6

include <BOSL2/std.scad>
cylinder(r1=25, r2=15, h=60, anchor=BOTTOM+FRONT);

Figure 7

Here we convert a 30 deg angle into an anchor using cylindrical_to_xyz()

include <BOSL2/std.scad>
cylinder(r1=25, r2=15, h=60, anchor=cylindrical_to_xyz(1,30,1));

Figure 8

For Spherical type attachables, you can pass a vector that points at any arbitrary place on the surface of the sphere:

include <BOSL2/std.scad>
sphere(r=50, anchor=TOP);

Figure 9

include <BOSL2/std.scad>
sphere(r=50, anchor=TOP+FRONT);

Figure 10

Here the spherical_to_xyz() function converts spherical coordinates into a vector you can use as an anchor:

include <BOSL2/std.scad>
sphere(r=50, anchor=spherical_to_xyz(1,-30,60));

Figure 11

Some attachable shapes may provide specific named anchors for shape-specific anchoring. These will be given as strings and will be specific to that type of attachable. When named anchors are supported, they are listed in a "Named Anchors" section of the documentation for the module. The teardrop() attachable, for example, has a named anchor called "cap" and in 2D the star() attachable has anchors labeled by tip number:

include <BOSL2/std.scad>
teardrop(d=100, l=20, anchor="cap");

Figure 12

include <BOSL2/std.scad>
star(n=7, od=30, id=20, anchor="tip2");

Figure 13

Some shapes, for backwards compatibility reasons, can take a center= argument. This just overrides the anchor= argument. A center=true argument is the same as anchor=CENTER. A center=false argument chooses the anchor to match the behavior of the builtin version: for a cube it is the same as anchor=[-1,-1,-1] but for a cylinder, it is the same as anchor=BOTTOM.

include <BOSL2/std.scad>
cube([50,40,30],center=true);

Figure 14

include <BOSL2/std.scad>
cube([50,40,30],center=false);

Figure 15

Most 2D shapes provided by BOSL2 are also anchorable. The built-in square() and circle() modules have been overridden to make them attachable.. The anchor= options for 2D shapes treat 2D vectors as expected. Special handling occurs with 3D vectors: if the Y coordinate is zero and the Z coordinate is nonzero, then the Z coordinate is used to replace the Y coordinate. This is done so that you can use the TOP and BOTTOM names as anchor for 2D shapes.

include <BOSL2/std.scad>
square([40,30], anchor=BACK+LEFT);

Figure 16

include <BOSL2/std.scad>
circle(d=50, anchor=BACK);

Figure 17

include <BOSL2/std.scad>
hexagon(d=50, anchor=LEFT);

Figure 18

include <BOSL2/std.scad>
pentagon(d=50, anchor=TOP);

Figure 20

Spin

You can spin attachable objects around the origin using the spin= argument. The spin applies after anchoring, so depending on how you anchor an object, its spin may not be about its center. This means that spin can have an effect even on rotationally symmetric objects like spheres and cylinders. You specify the spin in degrees. A positive number will result in a counter-clockwise spin around the Z axis (as seen from above), and a negative number will make a clockwise spin:

include <BOSL2/std.scad>
cube([20,20,40], center=true, spin=45);

Figure 21

This example shows a cylinder which has been anchored at its FRONT, with a rotated copy in gray. The rotation is performed around the origin, but the cylinder is off the origin, so the rotation does have an effect on the cylinder, even though the cylinder has rotational symmetry.

include <BOSL2/std.scad>
cylinder(h=40,d=20,anchor=FRONT+BOT);
%cylinder(h=40.2,d=20,anchor=FRONT+BOT,spin=40);

Figure 22

You can also apply spin to 2D shapes from BOSL2, though only by scalar angle:

include <BOSL2/std.scad>
square([40,30], spin=30);

Figure 23

include <BOSL2/std.scad>
ellipse(d=[40,30], spin=30);

Figure 24

Orientation

Another way to specify a rotation for an attachable shape, is to pass a 3D vector via the orient= argument. This lets you specify what direction to tilt the top of the shape towards. For example, you can make a cone that is tilted up and to the right like this:

include <BOSL2/std.scad>
cylinder(h=100, r1=50, r2=20, orient=UP+RIGHT);

Figure 25

More precisely, the Z direction of the shape is rotated to align with the vector you specify. Two dimensional attachables, which have no Z vector, do not accept the orient= argument.

Mixing Anchoring, Spin, and Orientation

When giving anchor=, spin=, and orient=, they are applied anchoring first, spin second, then orient last. For example, here's a cube:

include <BOSL2/std.scad>
cube([20,20,50]);

Figure 26

You can center it with an anchor=CENTER argument:

include <BOSL2/std.scad>
cube([20,20,50], anchor=CENTER);

Figure 27

Add a 45 degree spin:

include <BOSL2/std.scad>
cube([20,20,50], anchor=CENTER, spin=45);

Figure 28

Now tilt the top up and forward:

include <BOSL2/std.scad>
cube([20,20,50], anchor=CENTER, spin=45, orient=UP+FWD);

Figure 29

For 2D shapes, you can mix anchor= with spin=, but not with orient=.

include <BOSL2/std.scad>
square([40,30], anchor=BACK+LEFT, spin=30);

Figure 30

Positioning Children

Positioning is a powerful method for placing an object relative to another object. You do this by making the second object a child of the first object. By default, the child's anchor point will be aligned with the center of the parent. The default anchor for cyl() is CENTER, and in this case, the cylinder is centered on the cube's center

include <BOSL2/std.scad>
up(13) cube(50)
    cyl(d=25,l=95);

Figure 31

With cylinder() the default anchor is BOTTOM. It's hard to tell, but the cylinder's bottom is placed at the center of the cube.

include <BOSL2/std.scad>
cube(50)
    cylinder(d=25,h=75);

Figure 32

If you explicitly anchor the child object then the anchor you choose will be aligned with the center point of the parent object. In this example the right side of the cylinder is aligned with the center of the cube.

include <BOSL2/std.scad>
cube(50,anchor=FRONT)     
    cylinder(d=25,h=95,anchor=RIGHT);

Figure 33

The position() module enables you to specify where on the parent to position the child object. You give position() an anchor point on the parent, and the child's anchor point is aligned with the specified parent anchor point. In this example the LEFT anchor of the cylinder is positioned on the RIGHT anchor of the cube.

include <BOSL2/std.scad>
cube(50,anchor=FRONT)     
    position(RIGHT) cylinder(d=25,h=75,anchor=LEFT);

Figure 34

Using this mechanism you can position objects relative to other objects which are in turn positioned relative to other objects without having to keep track of the transformation math.

include <BOSL2/std.scad>
cube([50,50,30],center=true)
    position(TOP+RIGHT) cube([25,40,10], anchor=RIGHT+BOT)
       position(LEFT+FRONT+TOP) cube([12,12,8], anchor=LEFT+FRONT+BOT)
         cylinder(h=10,r=3);

Figure 35

The positioning mechanism is not magical: it simply applies a translate() operation to the child. You can still apply your own additional translations or other transformations if you wish. For example, you can position an object 5 units from the right edge:

include<BOSL2/std.scad>
cube([50,50,20],center=true)
    position(TOP+RIGHT) left(5) cube([4,50,10], anchor=RIGHT+BOT);

Figure 36

Positioning objects works the same way in 2D.

include<BOSL2/std.scad>
square(10)
    position(RIGHT) square(3,anchor=LEFT);

Figure 37

Using position() with orient()

When positioning an object near an edge or corner you may wish to orient the object relative to some face other than the TOP face that meets at that edge or corner. You can always apply rot() to change the orientation of the child object, but in order to do this, you need to figure out the correct rotation. The orient() module provides a mechanism for re-orienting the child() that eases this burden: it can orient the child relative to the parent anchor directions. This is different than giving an orient= argument to the child, because that orients relative to the parent's global coordinate system by just using the vector directly, instead of orienting to the parent's anchor, which takes account of face orientation. A series of three examples shows the different results. In the first example, we use only position(). The child cube is erected pointing upwards, in the Z direction. In the second example we use orient=RIGHT in the child and the result is that the child object points in the X+ direction, without regard for the shape of the parent object. In the final example we apply orient(RIGHT) and the child is oriented relative to the slanted right face of the parent using the parent RIGHT anchor.

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     cube([15,15,25],anchor=RIGHT+BOT);

Figure 38

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     cube([15,15,25],orient=RIGHT,anchor=LEFT+BOT);

Figure 39

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     orient(RIGHT)
        cube([15,15,25],anchor=BACK+BOT);

Figure 40

You may have noticed that the children in the above three examples have different anchors. Why is that? The first and second examples differ because anchoring up and anchoring to the right require anchoring on opposite sides of the child. But the third case differs because the spin has changed. The examples below show the same models but with arrows replacing the child cube. The red flags on the arrows mark the zero spin direction. Examine the red flags to see how the spin changes. The Y+ direction of the child will point towards that red flag.

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     anchor_arrow(40);

Figure 41

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     anchor_arrow(40, orient=RIGHT);

Figure 42

include<BOSL2/std.scad>
prismoid([50,50],[30,30],h=40)
  position(RIGHT+TOP)
     orient(RIGHT)
        anchor_arrow(40);

Figure 43

Aligning children with align()

You may have noticed that with position() and orient(), specifying the child anchors to position objects flush with their parent can be annoying, or sometimes even tricky. You can simplify this task by using the align() module. This module positions children on faces of a parent and aligns to edges or corners, while picking the correct anchor points on the children so that the children line up correctly with the parent.

In the simplest case, if you want to place a child on the RIGHT side of its parent, you need to anchor the child to its LEFT anchor:

include<BOSL2/std.scad>
cuboid([50,40,15])
    position(RIGHT)
        color("lightblue")cuboid(5,anchor=LEFT);

Figure 44

When you use align() it automatically determines the correct anchor to use for the child and this anchor overrides any anchor specified to the child: any anchor you specify for the child is ignored.

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(RIGHT)
        color("lightblue")cuboid(5);

Figure 45

To place the child on top of the parent in the corner you can do use align as shown below instead of specifying the RIGHT+FRONT+BOT anchor with position():

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,RIGHT+FRONT)
        color("lightblue")prismoid([10,5],[7,4],height=4);

Figure 46

Both position() and align() can accept a list of anchor locations and makes several copies of the children, but if you want the children positioned flush, each copy requires a different anchor, so it is impossible to do this with a single call to position(), but easily done using align():

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,[RIGHT,LEFT])
        color("lightblue")prismoid([10,5],[7,4],height=4);

Figure 47

If you want the children close to the edge but not actually flush you can use the inset= parameter of align to achieve this:

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,[FWD,RIGHT,LEFT,BACK],inset=3)
        color("lightblue")prismoid([10,5],[7,4],height=4);

Figure 48

If you spin the children then align will still do the right thing

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,[RIGHT,LEFT])
        color("lightblue")prismoid([10,5],[7,4],height=4,spin=90);

Figure 49

If you orient the object DOWN it will be attached from its top anchor, correctly aligned.

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,RIGHT)
        color("lightblue")prismoid([10,5],[7,4],height=4,orient=DOWN);

Figure 50

Note that align() never changes the orientation of the children. If you put the blue prismoid on the right side the anchors line up but the edges of the child and parent don't.

include<BOSL2/std.scad>
prismoid(50,30,25){
  align(RIGHT,TOP)
    color("lightblue")prismoid([10,5],[7,4],height=4);
}

Figure 51

If you apply spin that is not a multiple of 90 degrees then alignment will line up the corner

include<BOSL2/std.scad>
cuboid([50,40,15])
    align(TOP,RIGHT)
        color("lightblue")cuboid(8,spin=33);

Figure 52

You can also attach objects to a cylinder. If you use the usual cubic anchors then a cube will attach on a face as shown here:

include<BOSL2/std.scad>
cyl(h=20,d=10,$fn=128)
  align(RIGHT,TOP)
    color("lightblue")cuboid(5);

Figure 53

But with a cylinder you can choose an arbitrary horizontal angle for the anchor. If you do this, similar to the case of arbitrary spin, the cube will attach on the nearest corner.

include<BOSL2/std.scad>
cyl(h=20,d=10,$fn=128)
  align([1,.3],TOP)
    color("lightblue")cuboid(5);

Figure 54

Attachment overview

Attachables get their name from their ability to be attached to each other. Unlike with positioning, attaching changes the orientation of the child object. Think of it like sticking two objects together: when you attach an object, it appears on the parent relative to the local coordinate system of the parent at the anchor point. To understand what this means, imagine the perspective of an ant walking on a sphere. The meaning of UP varies depending on where on the sphere the ant is standing. If you attach a cylinder to the sphere then the cylinder will be "up" from the ant's perspective. The first example shows a cylinder placed with position() so it points up in the global parent coordinate system. The second example shows how attach() points the cylinder UP from the perspective of an ant standing at the anchor point on the sphere.

include<BOSL2/std.scad>
sphere(40)
    position(RIGHT+TOP) cylinder(r=8,h=20);

Figure 55

include<BOSL2/std.scad>
sphere(40)
    attach(RIGHT+TOP) cylinder(r=8,h=20);

Figure 56

In the example above, the cylinder's center point is attached to the sphere, pointing "up" from the perspective of the sphere's surface. For a sphere, a surface normal is defined everywhere that specifies what "up" means. But for other objects, it may not be so obvious. Usually at edges and corners the direction is the average of the direction of the faces that meet there.

When you specify an anchor you are actually specifying both an anchor point but also an anchor direction. If you want to visualize this direction you can use anchor arrows.

Anchor Directions and Anchor Arrows

For the ant on the sphere it is obvious which direction is UP; that direction corresponds to the Z+ axis. The location of the X and Y axes is less clear and in fact it may be arbitrary. One way that is useful to show the position and orientation of an anchor point is by attaching an anchor arrow to that anchor. As noted before, the small red flag points in the direction of the anchor's Y+ axis when the spin is zero.

include <BOSL2/std.scad>
cube(18, center=true)
    attach(LEFT+TOP)
        anchor_arrow();

Figure 57

For large objects, you can change the size of the arrow with the s= argument.

include <BOSL2/std.scad>
sphere(d=100)
    attach(LEFT+TOP)
        anchor_arrow(s=50);

Figure 58

To show all the standard cardinal anchor points, you can use the show_anchors() module.

include <BOSL2/std.scad>
cube(20, center=true)
    show_anchors();

Figure 59

include <BOSL2/std.scad>
cylinder(h=25, d=25, center=true)
    show_anchors();

Figure 60

include <BOSL2/std.scad>
sphere(d=40)
    show_anchors();

Figure 61

For large objects, you can again change the size of the arrows with the s= argument.

include <BOSL2/std.scad>
prismoid(150,60,100)
    show_anchors(s=45);

Figure 62

Parent-Child Anchor Attachment (Double Argument Attachment)

The attach() module has two different modes of operation, parent-child anchor attachment and parent anchor attachment. These are also called double argument attachment and single argument attachment. The parent-child anchor attachment, with two arguments, is usually easier to use and is more powerful because it supports alignment. When you use parent-child anchor attachment you give a parent anchor and a child anchor. Imagine pointing the anchor arrows on the two objects directly at each other and pushing them together in the direction of the arrows until they touch. In many of the examples below we show first the two objects with their anchor arrows and then the result of the attach operation using those anchors.

include <BOSL2/std.scad>
cube(50,anchor=BOT) attach(TOP,BOT) anchor_arrow(30);
right(60)cylinder(d1=30,d2=15,h=25) attach(BOT,BOT) anchor_arrow(30);

Figure 63

include <BOSL2/std.scad>
cube(50,anchor=BOT)
  attach(TOP,BOT) cylinder(d1=30,d2=15,h=25);

Figure 64

This example produces the same result as using align(), but if the parent anchor is not horizontal, then the child is reoriented:

include <BOSL2/std.scad>
prismoid([50,50],[35,35],h=50,anchor=BOT) attach(RIGHT,BOT) anchor_arrow(30);
right(60)cylinder(d1=30,d2=15,h=25) attach(BOT,BOT) anchor_arrow(30);

Figure 65

include <BOSL2/std.scad>
prismoid([50,50],[35,35],h=50,anchor=BOT)
  attach(RIGHT,BOT) cylinder(d1=30,d2=15,h=25);

Figure 66

In this case we attach the curved side of the cone to a cube by lining up the anchor arrows:

include <BOSL2/std.scad>
cube(50,center=true) attach(RIGHT,BOT) anchor_arrow(30);
right(80)cylinder(d1=30,d2=15,h=25) attach(LEFT,BOT) anchor_arrow(30);

Figure 67

include <BOSL2/std.scad>
cube(50,center=true)
  attach(RIGHT,LEFT) cylinder(d1=30,d2=15,h=25);

Figure 68

Note that this form of attachent overrides any anchor or orientation specified in the child: with parent-child anchor attachment the anchor= and orient= parameters to the child are ignored.

When you specify attachment using a pair of anchors, the attached child can spin around the parent anchor while still being attached at the designated anchors: specifying the anchors leaves one unspecified degree of freedom. As noted earlier, this ambiguity is resolved by anchors having a defined spin which specifies where the Y+ axis is located. The way that BOSL2 positions objects can be understood by viewing the anchor arrows as shown above, or you can remember these rules:

  1. When attaching to the TOP or BOTTOM: the FRONT of the child points to the front if possible; otherwise the TOP of the child points BACK.
  2. When attaching to other faces, if possible the child's UP anchor will point UP; otherwise, the BACK of the child points up (so the FRONT is pointed down).

To show how this works we use this prismoid where the blue arrow is pointing to the front and the green arrow points up. Also note that the front left edge is the only right angle.

include <BOSL2/std.scad>
color_this("orange")
prismoid([8,8],[6,6],shift=-[1,1],h=8) {
     attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
     attach(FWD,BOT) anchor_arrow(s=12);     
}

Figure 69

If we attach this to the TOP by the LEFT side then we get the result below. Notice how the green UP arrow is pointing back.

include <BOSL2/std.scad>
cube(30) attach(TOP,LEFT)
color_this("orange")
  prismoid([8,8],[6,6],shift=-[1,1],h=8) {
    attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
    attach(FWD,BOT) anchor_arrow(s=12);     
  }

Figure 70

If we attach to the RIGHT using the same LEFT side anchor on the prismoid then we get the result below. Note that the green UP anchor is pointing UP, in accordance with rule 2 from above.

include <BOSL2/std.scad>
cube(30) attach(RIGHT,LEFT)
color_this("orange")
  prismoid([8,8],[6,6],shift=-[1,1],h=8) {
    attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
    attach(FWD,BOT) anchor_arrow(s=12);     
  }

Figure 71

The green UP arrow can always be arranged to point up unless we attach either the top or bottom to one of the cube's vertical faces. Here we attach the bottom so you can still see both arrows. The blue FRONT arrow on the object is pointing down, as expected based on rule 2.

include <BOSL2/std.scad>
cube(30) attach(RIGHT,BOT)
color_this("orange")
  prismoid([8,8],[6,6],shift=-[1,1],h=8) {
    attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
    attach(FWD,BOT) anchor_arrow(s=12);     
  }

Figure 72

What do you do if the direction the child appears is not the direction you need? To address this issue attach() provides a spin= parameter which spins the attached child around the axis defined by the joined anchor vectors. Here is the last example with a rotation applied to bring the front anchor back to the front:

include <BOSL2/std.scad>
cube(30) attach(RIGHT,BOT,spin=-90)
color_this("orange")
  prismoid([8,8],[6,6],shift=-[1,1],h=8) {
    attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
    attach(FWD,BOT) anchor_arrow(s=12);     
  }

Figure 73

Be aware that specifying spin= to attach() is not equivalent to using the spin= argument to the child. Unlike orient= and anchor=, which are ignored, the child spin= argument is still respected, but it may be difficult to figure out which axis it will rotate on. It is more intuitive to ignore the child spin parameter and only use the spin parameter to attach(). The spin must be scalar but need not be a multiple of 90 degrees.

include <BOSL2/std.scad>
cube(30) attach(RIGHT,BOT,spin=-37)
color_this("orange")
  prismoid([8,8],[6,6],shift=-[1,1],h=8) {
    attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
    attach(FWD,BOT) anchor_arrow(s=12);     
  }

Figure 74

By default, attach() places the child exactly flush with the surface of the parent. Sometimes it's useful to have the child overlap the parent by translating it into the parent. You can do this with the overlap= argument to attach(). A positive value will cause the child to overlap the parent, and a negative value will move the child away from the parent, leaving a small gap. In the first example we use a very large value of overlap so the cube is sunk deeply into the parent. In the second example a large negative overlap value raises the child high above the parent.

include <BOSL2/std.scad>
cuboid(50)
    attach(TOP,BOT,overlap=15)
        color("green")cuboid(20);

Figure 75

include <BOSL2/std.scad>
cube(50,center=true)
    attach(TOP,BOT,overlap=-20)
        cyl(d=20,h=20);

Figure 76

Another feature provided by the double argument form of attach() is alignment, which works in a similar way to align(). You can specify align= to align the attached child to an edge or corner. The example below shows five different alignments.

include <BOSL2/std.scad>
module thing(){
  color_this("orange")
    prismoid([8,8],[6,6],shift=-[1,1],h=8) {
      attach(TOP,BOT) anchor_arrow(color=[0,1,0],s=12);
      attach(FWD,BOT) anchor_arrow(s=12);     
    }
}
prismoid([50,50],[35,35],h=25,anchor=BOT){
  attach(TOP,BOT,align=FRONT) thing();
  attach(RIGHT,BOT,align=BOT) thing();    
  attach(RIGHT,BACK,align=FRONT) thing();
  attach(FRONT,BACK,align=BOT,spin=45) thing();
  attach(TOP,RIGHT,align=RIGHT,spin=90) thing();
}

Figure 77

As with align() if you turn an object 90 degrees it can match up with parallel edges, but if you turn it an arbitrary angle, a corner of the child will contact the edge of the parent. Also like align() the anchor points of the parent and child are aligned but this does not necessarily mean that edges line up neatly when the shapes have varying angles. This misalignment is visible in the object attached at the RIGHT and aligned to the FRONT.

You may be wondering why all this fuss with align is necessary. Couldn't you just attach an object at an anchor on an edge? When you do this, the object will be attached using the edge anchor, which is not perpendicular to the faces of the object. The example below shows attachment to an edge anchor and also a corner anchor.

include <BOSL2/std.scad>
cube(30)
   color("orange"){
     attach(RIGHT+FRONT,BOT) 
        prismoid([8,8],[6,6],shift=-[1,1],h=8);
     attach(TOP+LEFT+FWD,BOT)
        prismoid([8,8],[6,6],shift=-[1,1],h=8);
   }

Figure 78

When using the align option to attach() you can also set inset, which works the same way as the inset parameter to align(). It shifts the child away from the edge or edges where it is aligned by the specified amount.

include <BOSL2/std.scad>
prismoid([50,50],[50,25],25){
  attach(FWD,BOT,align=TOP,inset=3) color("lavender")cuboid(5);
  attach(FWD,BOT,align=BOT+RIGHT,inset=3) color("purple")cuboid(5);
}

Figure 79

The last capability provided by attach() is to attach the child inside the parent object. This is useful if you want to subtract the child from the parent. Doing this requires using tagged operations with diff() which is explained in more detail below. For the examples here, note that the diff() and tag() operations that appear cause the child to be subtracted. We return to the example that started this section, with anchor arrows shown on the two objects.

include <BOSL2/std.scad>
cube(50,anchor=BOT) attach(TOP) anchor_arrow(30);
right(60)cylinder(d1=30,d2=15,h=25) attach(TOP) anchor_arrow(30);

Figure 80

Inside attachment is activated using inside=true and it lines up the anchor arrows so they point together the same direction instead of opposite directions like regular outside attachment. The result in this case is appears below, where we have cut away the front half to show the interior:

include <BOSL2/std.scad>
back_half(s=200)
diff()
cube(50,anchor=BOT)
  attach(TOP,TOP,inside=true)
    cylinder(d1=30,d2=15,h=25);

Figure 81

The top of the cavity has a thin layer on it, which occurs because the two objects share a face in the difference. To fix this you can use the shiftout parameter to attach(). In this case you could also use a negative overlay value, but the shiftout parameter shifts out in every direction that is needed, which may be three directions if you align the child at a corner. The above example looks like this with with the shift added:

include <BOSL2/std.scad>
back_half(s=200)
diff()
cube(50,anchor=BOT)
  attach(TOP,TOP,inside=true,shiftout=0.01)
    cylinder(d1=30,d2=15,h=25);

Figure 82

Here is an example of connecting the same object on the right, but this time with the BOTTOM anchor. Note how the BOTTOM anchor is aligned to the RIGHT so it is parallel and pointing in the same direction as the RIGHT anchor.

include <BOSL2/std.scad>
back_half(s=200)
diff()
cuboid(50)
  attach(RIGHT,BOT,inside=true,shiftout=0.01)
    cylinder(d1=30,d2=15,h=25);

Figure 83

Here is an example where alignment moves the object into the corner, and we benefit from shiftout providing 3 dimensions of adjustment:

include <BOSL2/std.scad>
diff()
cuboid(10)
  attach(TOP,TOP,align=RIGHT+FWD,inside=true,shiftout=.01)
    cuboid([2,5,9]);

Figure 84

As with position(), with any use of attach() you can still apply your own translations and other transformations even after attaching an object. However, the order of operations now matters. If you apply a translation outside of the anchor then it acts in the parent's global coordinate system, so the child moves up in this example, where the light gray shows the untranslated object.

include <BOSL2/std.scad>
cuboid(50){
  %attach(RIGHT,BOT)
    cyl(d1=30,d2=15,h=25);
  up(13)
    color("green") attach(RIGHT,BOT)
      cyl(d1=30,d2=15,h=25);
}

Figure 85

On the other hand, if you put the translation between the attach and the object in your code, then it will act in the local coordinate system of the parent at the parent's anchor, so in the example below it moves to the right.

include <BOSL2/std.scad>
cuboid(50){
  %attach(RIGHT,BOT)
    cyl(d1=30,d2=15,h=25);
  color("green") attach(RIGHT,BOT)
    up(13)
      cyl(d1=30,d2=15,h=25);
}

Figure 86

Parent-child Anchor attachment with CENTER anchors can be surprising because the anchors both point upwards, so in the example below, the child's CENTER anchor points up, so it is inverted when it is attached to the parent cone. Note that the anchors are CENTER anchors, so the bases of the anchors are hidden in the middle of the objects.

include <BOSL2/std.scad>
cylinder(d1=30,d2=15,h=25) attach(CENTER) anchor_arrow(40);
right(40)cylinder(d1=30,d2=15,h=25) attach(CENTER) anchor_arrow(40);

Figure 87

include <BOSL2/std.scad>
cylinder(d1=30,d2=15,h=25)
    attach(CENTER,CENTER)
        cylinder(d1=30,d2=15,h=25);

Figure 88

Is is also possible to attach to edges and corners of the parent object. The anchors for edges spin the child so its BACK direction is aligned with the edge. If the edge belongs to a top or bottom horizontal face, then the BACK directions will point clockwise around the face, as seen from outside the shape. (This is the same direction required for construction of valid faces in OpenSCAD.) Otherwise, the BACK direction will point upwards.

Examine the red flags below, where only edge anchors appear on a prismoid. The top face shows the red flags pointing clockwise. The sloped side edges point along the edges, generally upward, and the bottom ones appear to point counter-clockwise, but if we viewed the shape from the bottom they would also appear clockwise.

include <BOSL2/std.scad>
prismoid([100,175],[55,88], h=55)
  for(i=[-1:1], j=[-1:1], k=[-1:1])
    let(anchor=[i,j,k])
       if (sum(v_abs(anchor))==2)
         attach(anchor,BOT)anchor_arrow(40);

Figure 89

In this example cylinders sink half-way into the top edges of the prismoid:

include <BOSL2/std.scad>
$fn=16;
r=6;
prismoid([100,175],[55,88], h=55){
   attach([TOP+RIGHT,TOP+LEFT],LEFT,overlap=r/2) cyl(r=r,l=88+2*r,rounding=r);
   attach([TOP+FWD,TOP+BACK],LEFT,overlap=r/2) cyl(r=r,l=55+2*r, rounding=r);   
}

Figure 90

This type of edge attachment is useful for attaching 3d edge masks to edges:

include <BOSL2/std.scad>
$fn=32;
diff()
cuboid(75)
   attach([FRONT+LEFT, FRONT+RIGHT, BACK+LEFT, BACK+RIGHT],
          FWD+LEFT,inside=true)
     rounding_edge_mask(l=76, r1=8,r2=28);

Figure 91

Parent Anchor Attachment (Single Argument Attachment)

The second form of attachment is parent anchor attachment, which just uses a single argument. This form of attachment is less useful in general and does not provide alignment. When you give attach() a parent anchor but no child anchor it orients the child according to the parent anchor direction but then simply places the child based on its internally defined anchor at the parent anchor position. For most objects the default anchor is the CENTER anchor, so objects will appear sunk half-way into the parent.

include <BOSL2/std.scad>
cuboid(30)
    attach(TOP)
        color("green")cuboid(10);

Figure 92

Some objects such as cylinder(), prismoid(), and anchor_arrow() have default anchors on the bottom, so they will appear on the surface. For objects like this you can save a little bit of typing by using parent anchor attachment. But in the case of cube() the anchor is not centered, so the result is:

include <BOSL2/std.scad>
cube(30)
    attach(TOP)
        color("green")cube(10);

Figure 93

In order to make single argument attachment produce the results you need you will probably need to change the child anchor. Note that unlike parent-child anchor attachment, with parent anchor attachment the anchor= and orient= arguments are respected. We could therefore place a cuboid like this:

include <BOSL2/std.scad>
cuboid(30)
  attach(RIGHT)
      color("green")cuboid(10,anchor=BOT);

Figure 94

If you need to place a cuboid at the anchor point but need it anchored relative to one of the bottom edge or corner anchors then you can do that with parent anchor attachment:

include <BOSL2/std.scad>
cuboid(30)
  attach(RIGHT)
      color("green")cuboid(10,anchor=BOT+FWD);

Figure 95

Another case where single argument attachment is useful is when the child doesn't have proper attachment support. If you use double argument attachment in such cases the results will be incorrect because the child doesn't properly respond to the internally propagated anchor directives. With single argument attachment, this is not a problem: the origin of the child will be placed at the parent anchor point. One module without attachment support is linear_extrude().

include <BOSL2/std.scad>
cuboid(20)
  attach(RIGHT)
     color("red")linear_extrude(height=2) star(n=7,ir=3,or=7);

Figure 96

As noted earlier, you can set orient= for children with parent anchor attachment, though the behavior may not be intuitive because the attachment process transforms the coordinate system and the orientation is done in the attached coordinate system. It may be helpful to start with the object attached to TOP and recall the rules from the previous section about how orientation works. The same rules apply here. Note that the forward arrow is pointing down after attaching the object on the RIGHT face.

include <BOSL2/std.scad>
cuboid(20){
  attach(RIGHT)
     color_this("red")cuboid([2,4,8],orient=RIGHT,anchor=RIGHT)
        attach(FWD) anchor_arrow();
  attach(TOP)
     color_this("red")cuboid([2,4,8],orient=RIGHT,anchor=RIGHT)
            attach(FWD) anchor_arrow();
}

Figure 97

Positioning and Attaching Multiple Children

You can attach or position more than one child at a time by enclosing them all in braces:

include <BOSL2/std.scad>
cube(50, center=true) {
    attach(TOP) cylinder(d1=50,d2=20,h=20);
    position(RIGHT) cylinder(d1=50,d2=20,h=20);
}

Figure 98

If you want to attach the same shape to multiple places on the same parent, you can pass the desired anchors as a list to the attach() or position() modules:

include <BOSL2/std.scad>
cube(50, center=true)
    attach([RIGHT,FRONT],TOP) cylinder(d1=35,d2=20,h=25);

Figure 99

include <BOSL2/std.scad>
cube(50, center=true)
    position([TOP,RIGHT,FRONT]) cylinder(d1=35,d2=20,h=25);

Figure 100

Attaching 2D Children

You can use attachments in 2D as well. As usual for the 2D case you can use TOP and BOTTOM as alternative to BACK and FORWARD. With parent-child anchor attachment you cannot use the spin parameter to attach() nor can you specify spin to the child. Spinning the child on the Z axis would rotate the anchor arrows out of alignment.

include <BOSL2/std.scad>
rect(50){
    attach(RIGHT,FRONT)
        color("red")trapezoid(w1=30,w2=0,h=30);
    attach(LEFT,FRONT,align=[FRONT,BACK],inset=3)
        color("green") trapezoid(w1=25, w2=0,h=30);
}

Figure 101

include <BOSL2/std.scad>
diff()
circle(d=50){
    attach(TOP,BOT,overlap=5)
        trapezoid(w1=30,w2=0,h=30);
    attach(BOT,BOT,inside=true)
        tag("remove")
        trapezoid(w1=30,w2=0,h=30);
}

Figure 102

Tagged Operations

BOSL2 introduces the concept of tags. Tags are names that can be given to attachables, so that you can refer to them when performing diff(), intersect(), and conv_hull() operations. Each object can have no more than one tag at a time.

diff([remove], [keep])

The diff() operator is used to difference away all shapes marked with the tag(s) given to remove, from the other shapes.

For example, to difference away a child cylinder from the middle of a parent cube, you can do this:

include <BOSL2/std.scad>
diff("hole")
cube(100, center=true)
    tag("hole")cylinder(h=101, d=50, center=true);

Figure 103

The keep= argument takes tags for shapes that you want to keep in the output.

include <BOSL2/std.scad>
diff("dish", keep="antenna")
cube(100, center=true)
    attach([FRONT,TOP], overlap=33) {
        tag("dish") cylinder(h=33.1, d1=0, d2=95);
        tag("antenna") cylinder(h=33.1, d=10);
    }

Figure 104

Remember that tags applied with tag() are inherited by children. In this case, we need to explicitly untag the first cylinder (or change its tag to something else), or it will inherit the "keep" tag and get kept.

include <BOSL2/std.scad>
diff("hole", "keep")
tag("keep")cube(100, center=true)
    attach([RIGHT,TOP]) {
        tag("") cylinder(d=95, h=5);
        tag("hole") cylinder(d=50, h=11, anchor=CTR);
    }

Figure 105

You can apply a tag that is not propagated to the children using tag_this(). The above example could then be redone:

diff("hole", "keep") tag_this("keep")cube(100, center=true) attach([RIGHT,TOP]) { cylinder(d=95, h=5); tag("hole") cylinder(d=50, h=11, anchor=CTR); }

You can of course apply tag() to several children.

include <BOSL2/std.scad>
diff("hole")
cube(100, center=true)
    attach([FRONT,TOP], overlap=20)
        tag("hole") {
            cylinder(h=20.1, d1=0, d2=95);
            down(10) cylinder(h=30, d=30);
        }

Figure 106

Many of the modules that use tags have default values for their tags. For diff the default remove tag is "remove" and the default keep tag is "keep". In this example we rely on the default values:

include <BOSL2/std.scad>
diff()
sphere(d=100) {
    tag("keep")xcyl(d=40, l=120);
    tag("remove")cuboid([40,120,100]);
}

Figure 107

The parent object can be differenced away from other shapes. Tags are inherited by children, though, so you will need to set the tags of the children as well as the parent.

include <BOSL2/std.scad>
diff("hole")
tag("hole")cube([20,11,45], center=true)
    tag("body")cube([40,10,90], center=true);

Figure 108

Tags (and therefore tag-based operations like diff()) only work correctly with attachable children. However, a number of built-in modules for making shapes are not attachable. Some notable non-attachable modules are text(), linear_extrude(), rotate_extrude(), polygon(), polyhedron(), import(), surface(), union(), difference(), intersection(), offset(), hull(), and minkowski().

To allow you to use tags-based operations with non-attachable shapes, you can wrap them with the force_tag() module to specify their tags. For example:

include <BOSL2/std.scad>
diff("hole")
cuboid(50)
  attach(TOP)
    force_tag("hole")
      rotate_extrude()
        right(15)
          square(10,center=true);

Figure 109

intersect([intersect], [keep])

To perform an intersection of attachables, you can use the intersect() module. This is specifically intended to address the situation where you want intersections involving a parent and a child, something that is impossible with the native intersection() module. This module treats the children in three groups: objects matching the intersect tags, objects matching the tags listed in keep and the remaining objects that don't match any listed tags. The intersection is computed between the union of the intersect tagged objects and the union of the objects that don't match any listed tags. Finally the objects listed in keep are union ed with the result.

In this example the parent (untagged) is intersected with a conical bounding shape, which is tagged with the intersect tag.

include <BOSL2/std.scad>
intersect("bounds")
cube(100, center=true)
    tag("bounds") cylinder(h=100, d1=120, d2=95, center=true, $fn=72);

Figure 110

In this example the child objects are intersected with the bounding box parent.

include <BOSL2/std.scad>
intersect("pole cap")
cube(100, center=true)
    attach([TOP,RIGHT]) {
        tag("pole")cube([40,40,80],center=true);
        tag("cap")sphere(d=40*sqrt(2));
    }

Figure 111

The default intersect tag is "intersect" and the default keep tag is "keep". Here is an example where "keep" is used to keep the pole from being removed by the intersection.

include <BOSL2/std.scad>
intersect()
cube(100, center=true) {
    tag("intersect")cylinder(h=100, d1=120, d2=95, center=true, $fn=72);
    tag("keep")zrot(45) xcyl(h=140, d=20, $fn=36);
}

Figure 112

conv_hull([keep])

You can use the conv_hull() module to hull shapes together. Objects marked with the keep tags are excluded from the hull and unioned into the final result. The default keep tag is "keep".

include <BOSL2/std.scad>
conv_hull()
cube(50, center=true) {
    cyl(h=100, d=20);
    tag("keep")xcyl(h=100, d=20);
}

Figure 113

3D Masking Attachments

To make it easier to mask away shapes from various edges of an attachable parent shape, there are a few specialized alternatives to the attach() and position() modules.

edge_mask()

If you have a 3D mask shape that you want to difference away from various edges, you can use the edge_mask() module. This module will take a vertically oriented shape, and will rotate and move it such that the BACK, RIGHT (X+,Y+) side of the shape will be aligned with the given edges. The shape will be tagged as a "remove" so that you can use diff() with its default "remove" tag. For example, here's a shape for rounding an edge:

include <BOSL2/std.scad>
module round_edge(l,r) difference() {
    translate([-1,-1,-l/2])
        cube([r+1,r+1,l]);
    translate([r,r])
        cylinder(h=l+1,r=r,center=true, $fn=quantup(segs(r),4));
}
round_edge(l=30, r=19);

Figure 114

You can use that mask to round various edges of a cube:

include <BOSL2/std.scad>
module round_edge(l,r) difference() {
    translate([-1,-1,-l/2])
        cube([r+1,r+1,l]);
    translate([r,r])
        cylinder(h=l+1,r=r,center=true, $fn=quantup(segs(r),4));
}
diff()
cube([50,60,70],center=true)
    edge_mask([TOP,"Z"],except=[BACK,TOP+LEFT])
        round_edge(l=71,r=10);

Figure 115

corner_mask()

If you have a 3D mask shape that you want to difference away from various corners, you can use the corner_mask() module. This module will take a shape and rotate and move it such that the BACK RIGHT TOP (X+,Y+,Z+) side of the shape will be aligned with the given corner. The shape will be tagged as a "remove" so that you can use diff() with its default "remove" tag. For example, here's a shape for rounding a corner:

include <BOSL2/std.scad>
module round_corner(r) difference() {
    translate(-[1,1,1])
        cube(r+1);
    translate([r,r,r])
        spheroid(r=r, style="aligned", $fn=quantup(segs(r),4));
}
round_corner(r=10);

Figure 116

You can use that mask to round various corners of a cube:

include <BOSL2/std.scad>
module round_corner(r) difference() {
    translate(-[1,1,1])
        cube(r+1);
    translate([r,r,r])
        spheroid(r=r, style="aligned", $fn=quantup(segs(r),4));
}
diff()
cube([50,60,70],center=true)
    corner_mask([TOP,FRONT],LEFT+FRONT+TOP)
        round_corner(r=10);

Figure 117

Mix and Match Masks

You can use edge_mask() and corner_mask() together as well:

include <BOSL2/std.scad>
module round_corner(r) difference() {
    translate(-[1,1,1])
        cube(r+1);
    translate([r,r,r])
        spheroid(r=r, style="aligned", $fn=quantup(segs(r),4));
}
module round_edge(l,r) difference() {
    translate([-1,-1,-l/2])
        cube([r+1,r+1,l]);
    translate([r,r])
        cylinder(h=l+1,r=r,center=true, $fn=quantup(segs(r),4));
}
diff()
cube([50,60,70],center=true) {
    edge_mask("ALL") round_edge(l=71,r=10);
    corner_mask("ALL") round_corner(r=10);
}

Figure 118

2D Profile Mask Attachments

While 3D mask shapes give you a great deal of control, you need to make sure they are correctly sized, and you need to provide separate mask shapes for corners and edges. Often, a single 2D profile could be used to describe the edge mask shape (via linear_extrude()), and the corner mask shape (via rotate_extrude()). This is where edge_profile(), corner_profile(), and face_profile() come in.

edge_profile()

Using the edge_profile() module, you can provide a 2D profile shape and it will be linearly extruded to a mask of the appropriate length for each given edge. The resultant mask will be tagged with "remove" so that you can difference it away with diff() with the default "remove" tag. The 2D profile is assumed to be oriented with the BACK, RIGHT (X+,Y+) quadrant as the "cutter edge" that gets re-oriented towards the edges of the parent shape. A typical mask profile for chamfering an edge may look like:

include <BOSL2/std.scad>
mask2d_roundover(10);

Figure 119

Using that mask profile, you can mask the edges of a cube like:

include <BOSL2/std.scad>
diff()
cube([50,60,70],center=true)
   edge_profile("ALL")
       mask2d_roundover(10);

Figure 120

corner_profile()

You can use the same profile to make a rounded corner mask as well:

include <BOSL2/std.scad>
diff()
cube([50,60,70],center=true)
   corner_profile("ALL", r=10)
       mask2d_roundover(10);

Figure 121

face_profile()

As a simple shortcut to apply a profile mask to all edges and corners of a face, you can use the face_profile() module:

include <BOSL2/std.scad>
diff()
cube([50,60,70],center=true)
   face_profile(TOP, r=10)
       mask2d_roundover(10);

Figure 122

Coloring Attachables

Usually, when coloring a shape with the color() module, the parent color overrides the colors of all children. This is often not what you want:

include <BOSL2/std.scad>
$fn = 24;
color("red") spheroid(d=3) {
    attach(CENTER,BOT) color("white") cyl(h=10, d=1) {
        attach(TOP,BOT) color("green") cyl(h=5, d1=3, d2=0);
    }
}

Figure 123

If you use the recolor() module, however, the child's color overrides the color of the parent. This is probably easier to understand by example:

include <BOSL2/std.scad>
$fn = 24;
recolor("red") spheroid(d=3) {
    attach(CENTER,BOT) recolor("white") cyl(h=10, d=1) {
        attach(TOP,BOT) recolor("green") cyl(h=5, d1=3, d2=0);
    }
}

Figure 124

Be aware that recolor() will only work if you avoid using the native color() module. Also note that recolor() still affects all its children. If you want to color an object without affecting the children you can use color_this(). See the difference below:

include <BOSL2/std.scad>
$fn = 24;
recolor("red") spheroid(d=3) {
    attach(CENTER,BOT) recolor("white") cyl(h=10, d=1) {
        attach(TOP,BOT)  cyl(h=5, d1=3, d2=0);
    }
}
right(5)
recolor("red") spheroid(d=3) {
    attach(CENTER,BOT) color_this("white") cyl(h=10, d=1) {
        attach(TOP,BOT)  cyl(h=5, d1=3, d2=0);
    }
}

Figure 125

As with all of the attachable features, these color modules only work on attachable objects, so they will have no effect on objects you create using linear_extrude() or rotate_extrude().

Making Attachables

To make a shape attachable, you just need to wrap it with an attachable() module with a basic description of the shape's geometry. By default, the shape is expected to be centered at the origin. The attachable() module expects exactly two children. The first will be the shape to make attachable, and the second will be children(), literally.

Pass-through Attachables

The simplest way to make your own attachable module is to simply pass through to a pre-existing attachable submodule. This could be appropriate if you want to rename a module, or if the anchors of an existing module are suited to (or good enough for) your object. In order for your attachable module to work properly you need to accept the anchor, spin and orient parameters, give them suitable defaults, and pass them to the attachable submodule. Don't forget to pass the children to the attachable submodule as well, or your new module will ignore its children.

include <BOSL2/std.scad>
$fn=32;
module cutcube(anchor=CENTER,spin=0,orient=UP)
{
   tag_scope(){
     diff()
       cuboid(15, rounding=2, anchor=anchor,spin=spin,orient=orient){
         tag("remove")attach(TOP)cuboid(5);
         children();
       }
   }
}
diff()
cutcube()
  tag("remove")attach(RIGHT) cyl(d=2,h=8);

Figure 126

Prismoidal/Cuboidal Attachables

To make a cuboidal or prismoidal shape attachable, you use the size, size2, and offset arguments of attachable().

In the most basic form, where the shape is fully cuboid, with top and bottom of the same size, and directly over one another, you can just use size=.

include <BOSL2/std.scad>
module cubic_barbell(s=100, anchor=CENTER, spin=0, orient=UP) {
    attachable(anchor,spin,orient, size=[s*3,s,s]) {
        union() {
            xcopies(2*s) cube(s, center=true);
            xcyl(h=2*s, d=s/4);
        }
        children();
    }
}
cubic_barbell(100) show_anchors(60);

Figure 127

When the shape is prismoidal, where the top is a different size from the bottom, you can use the size2= argument as well. While size= takes all three axes sizes, the size2= argument only takes the [X,Y] sizes of the top of the shape.

include <BOSL2/std.scad>
module prismoidal(size=[100,100,100], scale=0.5, anchor=CENTER, spin=0, orient=UP) {
    attachable(anchor,spin,orient, size=size, size2=[size.x, size.y]*scale) {
        hull() {
            up(size.z/2-0.005)
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y]*scale, center=true);
            down(size.z/2-0.005)
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y], center=true);
        }
        children();
    }
}
prismoidal([100,60,30], scale=0.5) show_anchors(20);

Figure 128

When the top of the prismoid can be shifted away from directly above the bottom, you can use the shift= argument. The shift= argument takes an [X,Y] vector of the offset of the center of the top from the XY center of the bottom of the shape.

include <BOSL2/std.scad>
module prismoidal(size=[100,100,100], scale=0.5, shift=[0,0], anchor=CENTER, spin=0, orient=UP) {
    attachable(anchor,spin,orient, size=size, size2=[size.x, size.y]*scale, shift=shift) {
        hull() {
            translate([shift.x, shift.y, size.z/2-0.005])
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y]*scale, center=true);
            down(size.z/2-0.005)
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y], center=true);
        }
        children();
    }
}
prismoidal([100,60,30], scale=0.5, shift=[-30,20]) show_anchors(20);

Figure 129

In the case that the prismoid is not oriented vertically, (ie, where the shift= or size2= arguments should refer to a plane other than XY) you can use the axis= argument. This lets you make prismoids naturally oriented forwards/backwards or sideways.

include <BOSL2/std.scad>
module yprismoidal(
    size=[100,100,100], scale=0.5, shift=[0,0],
    anchor=CENTER, spin=0, orient=UP
) {
    attachable(
        anchor, spin, orient,
        size=size, size2=point2d(size)*scale,
        shift=shift, axis=BACK
    ) {
        xrot(-90) hull() {
            translate([shift.x, shift.y, size.z/2-0.005])
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y]*scale, center=true);
            down(size.z/2-0.005)
                linear_extrude(height=0.01, center=true)
                    square([size.x,size.y], center=true);
        }
        children();
    }
}
yprismoidal([100,60,30], scale=1.5, shift=[20,20]) show_anchors(20);

Figure 130

Cylindrical Attachables

To make a cylindrical shape attachable, you use the l, and r/d, args of attachable().

include <BOSL2/std.scad>
module twistar(l,r,d, anchor=CENTER, spin=0, orient=UP) {
    r = get_radius(r=r,d=d,dflt=1);
    attachable(anchor,spin,orient, r=r, l=l) {
        linear_extrude(height=l, twist=90, slices=20, center=true, convexity=4)
            star(n=20, r=r, ir=r*0.9);
        children();
    }
}
twistar(l=100, r=40) show_anchors(20);

Figure 131

If the cylinder is elipsoidal in shape, you can pass the unequal X/Y sizes as a 2-item vector to the r= or d= argument.

include <BOSL2/std.scad>
module ovalstar(l,rx,ry, anchor=CENTER, spin=0, orient=UP) {
    attachable(anchor,spin,orient, r=[rx,ry], l=l) {
        linear_extrude(height=l, center=true, convexity=4)
            scale([1,ry/rx,1])
                star(n=20, r=rx, ir=rx*0.9);
        children();
    }
}
ovalstar(l=100, rx=50, ry=30) show_anchors(20);

Figure 132

For cylindrical shapes that aren't oriented vertically, use the axis= argument.

include <BOSL2/std.scad>
module ytwistar(l,r,d, anchor=CENTER, spin=0, orient=UP) {
    r = get_radius(r=r,d=d,dflt=1);
    attachable(anchor,spin,orient, r=r, l=l, axis=BACK) {
        xrot(-90)
            linear_extrude(height=l, twist=90, slices=20, center=true, convexity=4)
                star(n=20, r=r, ir=r*0.9);
        children();
    }
}
ytwistar(l=100, r=40) show_anchors(20);

Figure 133

Conical Attachables

To make a conical shape attachable, you use the l, r1/d1, and r2/d2, args of attachable().

include <BOSL2/std.scad>
module twistar(l, r,r1,r2, d,d1,d2, anchor=CENTER, spin=0, orient=UP) {
    r1 = get_radius(r1=r1,r=r,d1=d1,d=d,dflt=1);
    r2 = get_radius(r1=r2,r=r,d1=d2,d=d,dflt=1);
    attachable(anchor,spin,orient, r1=r1, r2=r2, l=l) {
        linear_extrude(height=l, twist=90, scale=r2/r1, slices=20, center=true, convexity=4)
            star(n=20, r=r1, ir=r1*0.9);
        children();
    }
}
twistar(l=100, r1=40, r2=20) show_anchors(20);

Figure 134

If the cone is ellipsoidal in shape, you can pass the unequal X/Y sizes as a 2-item vectors to the r1=/r2= or d1=/d2= arguments.

include <BOSL2/std.scad>
module ovalish(l,rx1,ry1,rx2,ry2, anchor=CENTER, spin=0, orient=UP) {
    attachable(anchor,spin,orient, r1=[rx1,ry1], r2=[rx2,ry2], l=l) {
        hull() {
            up(l/2-0.005)
                linear_extrude(height=0.01, center=true)
                    ellipse([rx2,ry2]);
            down(l/2-0.005)
                linear_extrude(height=0.01, center=true)
                    ellipse([rx1,ry1]);
        }
        children();
    }
}
ovalish(l=100, rx1=50, ry1=30, rx2=30, ry2=50) show_anchors(20);

Figure 135

For conical shapes that are not oriented vertically, use the axis= argument to indicate the direction of the primary shape axis:

include <BOSL2/std.scad>
module ytwistar(l, r,r1,r2, d,d1,d2, anchor=CENTER, spin=0, orient=UP) {
    r1 = get_radius(r1=r1,r=r,d1=d1,d=d,dflt=1);
    r2 = get_radius(r1=r2,r=r,d1=d2,d=d,dflt=1);
    attachable(anchor,spin,orient, r1=r1, r2=r2, l=l, axis=BACK) {
        xrot(-90)
            linear_extrude(height=l, twist=90, scale=r2/r1, slices=20, center=true, convexity=4)
                star(n=20, r=r1, ir=r1*0.9);
        children();
    }
}
ytwistar(l=100, r1=40, r2=20) show_anchors(20);

Figure 136

Spherical Attachables

To make a spherical shape attachable, you use the r/d args of attachable().

include <BOSL2/std.scad>
module spikeball(r, d, anchor=CENTER, spin=0, orient=UP) {
    r = get_radius(r=r,d=d,dflt=1);
    attachable(anchor,spin,orient, r=r*1.1) {
        union() {
            sphere_copies(r=r, n=512, cone_ang=180) cylinder(r1=r/10, r2=0, h=r/10);
            sphere(r=r);
        }
        children();
    }
}
spikeball(r=50) show_anchors(20);

Figure 137

If the shape is an ellipsoid, you can pass a 3-item vector of sizes to r= or d=.

include <BOSL2/std.scad>
module spikeball(r, d, scale, anchor=CENTER, spin=0, orient=UP) {
    r = get_radius(r=r,d=d,dflt=1);
    attachable(anchor,spin,orient, r=r*1.1*scale) {
        union() {
            sphere_copies(r=r, n=512, scale=scale, cone_ang=180) cylinder(r1=r/10, r2=0, h=r/10);
            scale(scale) sphere(r=r);
        }
        children();
    }
}
spikeball(r=50, scale=[0.75,1,1.5]) show_anchors(20);

Figure 138

VNF Attachables

If the shape just doesn't fit into any of the above categories, and you constructed it as a VNF, you can use the VNF itself to describe the geometry with the vnf= argument.

There are two variations to how anchoring can work for VNFs. When extent=true, (the default) then a plane is projected out from the origin, perpendicularly in the direction of the anchor, to the furthest distance that intersects with the VNF shape. The anchor point is then the center of the points that still intersect that plane.

include <BOSL2/std.scad>
module stellate_cube(s=100, anchor=CENTER, spin=0, orient=UP) {
    s2 = 3 * s;
    verts = [
        [0,0,-s2*sqrt(2)/2],
        each down(s/2, p=path3d(square(s,center=true))),
        each zrot(45, p=path3d(square(s2,center=true))),
        each up(s/2, p=path3d(square(s,center=true))),
        [0,0,s2*sqrt(2)/2]
    ];
    faces = [
        [0,2,1], [0,3,2], [0,4,3], [0,1,4],
        [1,2,6], [1,6,9], [6,10,9], [2,10,6],
        [1,5,4], [1,9,5], [9,12,5], [5,12,4],
        [4,8,3], [4,12,8], [12,11,8], [11,3,8],
        [2,3,7], [3,11,7], [7,11,10], [2,7,10],
        [9,10,13], [10,11,13], [11,12,13], [12,9,13]
    ];
    vnf = [verts, faces];
    attachable(anchor,spin,orient, vnf=vnf) {
        vnf_polyhedron(vnf);
        children();
    }
}
stellate_cube(25) {
    attach(UP+RIGHT) {
        anchor_arrow(20);
        %cube([100,100,0.1],center=true);
    }
}

Figure 139

When extent=false, then the anchor point will be the furthest intersection of the VNF with the anchor ray from the origin. The orientation of the anchor point will be the normal of the face at the intersection. If the intersection is at an edge or corner, then the orientation will bisect the angles between the faces.

include <BOSL2/std.scad>
module stellate_cube(s=100, anchor=CENTER, spin=0, orient=UP) {
    s2 = 3 * s;
    verts = [
        [0,0,-s2*sqrt(2)/2],
        each down(s/2, p=path3d(square(s,center=true))),
        each zrot(45, p=path3d(square(s2,center=true))),
        each up(s/2, p=path3d(square(s,center=true))),
        [0,0,s2*sqrt(2)/2]
    ];
    faces = [
        [0,2,1], [0,3,2], [0,4,3], [0,1,4],
        [1,2,6], [1,6,9], [6,10,9], [2,10,6],
        [1,5,4], [1,9,5], [9,12,5], [5,12,4],
        [4,8,3], [4,12,8], [12,11,8], [11,3,8],
        [2,3,7], [3,11,7], [7,11,10], [2,7,10],
        [9,10,13], [10,11,13], [11,12,13], [12,9,13]
    ];
    vnf = [verts, faces];
    attachable(anchor,spin,orient, vnf=vnf, extent=false) {
        vnf_polyhedron(vnf);
        children();
    }
}
stellate_cube() show_anchors(50);

Figure 140

include <BOSL2/std.scad>
$fn=32;
R = difference(circle(10), right(2, circle(9)));
linear_sweep(R,height=10,atype="hull")
    attach(RIGHT) anchor_arrow();

Figure 141

Making Named Anchors

While vector anchors are often useful, sometimes there are logically extra attachment points that aren't on the perimeter of the shape. This is what named string anchors are for. For example, the teardrop() shape uses a cylindrical geometry for it's vector anchors, but it also provides a named anchor "cap" that is at the tip of the hat of the teardrop shape.

Named anchors are passed as an array of named_anchor()s to the anchors= argument of attachable(). The named_anchor() call takes a name string, a positional point, an orientation vector, and a spin. The name is the name of the anchor. The positional point is where the anchor point is at. The orientation vector is the direction that a child attached at that anchor point should be oriented. The spin is the number of degrees that an attached child should be rotated counter-clockwise around the orientation vector. Spin is optional, and defaults to 0.

To make a simple attachable shape similar to a teardrop() that provides a "cap" anchor, you may define it like this:

include <BOSL2/std.scad>
module raindrop(r, thick, anchor=CENTER, spin=0, orient=UP) {
    anchors = [
        named_anchor("cap", [0,r/sin(45),0], BACK, 0)
    ];
    attachable(anchor,spin,orient, r=r, l=thick, anchors=anchors) {
        linear_extrude(height=thick, center=true) {
            circle(r=r);
            back(r*sin(45)) zrot(45) square(r, center=true);
        }
        children();
    }
}
raindrop(r=25, thick=20, anchor="cap");

Figure 142

If you want multiple named anchors, just add them to the list of anchors:

include <BOSL2/std.scad>
module raindrop(r, thick, anchor=CENTER, spin=0, orient=UP) {
    anchors = [
        named_anchor("captop", [0,r/sin(45), thick/2], BACK+UP,   0),
        named_anchor("cap",    [0,r/sin(45), 0      ], BACK,      0),
        named_anchor("capbot", [0,r/sin(45),-thick/2], BACK+DOWN, 0)
    ];
    attachable(anchor,spin,orient, r=r, l=thick, anchors=anchors) {
        linear_extrude(height=thick, center=true) {
            circle(r=r);
            back(r*sin(45)) zrot(45) square(r, center=true);
        }
        children();
    }
}
raindrop(r=15, thick=10) show_anchors();

Figure 143

Sometimes the named anchor you want to add may be at a point that is reached through a complicated set of translations and rotations. One quick way to calculate that point is to reproduce those transformations in a transformation matrix chain. This is simplified by how you can use the function forms of almost all the transformation modules to get the transformation matrices, and chain them together with matrix multiplication. For example, if you have:

scale([1.1, 1.2, 1.3]) xrot(15) zrot(25) right(20) sphere(d=1);

and you want to calculate the center point of the sphere, you can do it like:

sphere_pt = apply(
    scale([1.1, 1.2, 1.3]) * xrot(15) * zrot(25) * right(20),
    [0,0,0]
);

Overriding Standard Anchors

Sometimes you may want to use the standard anchors but override some of them. Returning to the square barebell example above, the anchors at the right and left sides are on the cubes at each end, but the anchors at x=0 are in floating in space. For prismoidal/cubic anchors in 3D and trapezoidal/rectangular anchors in 2D we can override a single anchor by specifying the override option and giving the anchor that is being overridden, and then the replacement in the form [position, direction, spin]. Most often you will only want to override the position. If you omit the other list items then the value drived from the standard anchor will be used. Below we override position of the FWD anchor:

include<BOSL2/std.scad>
module cubic_barbell(s=100, anchor=CENTER, spin=0, orient=UP) {
    override = [
                 [FWD,  [[0,-s/8,0]]]
               ];
    attachable(anchor,spin,orient, size=[s*3,s,s],override=override) {
        union() {
            xcopies(2*s) cube(s, center=true);
            xcyl(h=2*s, d=s/4);
        }
        children();
    }
}
cubic_barbell(100) show_anchors(60);

Figure 144

Note how the FWD anchor is now rooted on the cylindrical portion. If you wanted to also change its direction and spin you could do it like this:

include<BOSL2/std.scad>
module cubic_barbell(s=100, anchor=CENTER, spin=0, orient=UP) {
    override = [
                 [FWD,  [[0,-s/8,0], FWD+LEFT, 225]]
               ];
    attachable(anchor,spin,orient, size=[s*3,s,s],override=override) {
        union() {
            xcopies(2*s) cube(s, center=true);
            xcyl(h=2*s, d=s/4);
        }
        children();
    }
}
cubic_barbell(100) show_anchors(60);

Figure 145

In the above example we give three values for the override. As before, the first one places the anchor on the cylinder. We have added the second entry which points the anchor off to the left. The third entry gives a spin override, whose effect is shown by the position of the red flag on the arrow. If you want to override all of the x=0 anchors to be on the cylinder, with their standard directions, you can do that by supplying a list:

include<BOSL2/std.scad>
module cubic_barbell(s=100, anchor=CENTER, spin=0, orient=UP) {
    override = [
                 for(j=[-1:1:1], k=[-1:1:1])
                   if ([j,k]!=[0,0]) [[0,j,k], [s/8*unit([0,j,k])]]
               ];
    attachable(anchor,spin,orient, size=[s*3,s,s],override=override) {
        union() {
            xcopies(2*s) cube(s, center=true);
            xcyl(h=2*s, d=s/4);
        }
        children();
    }
}
cubic_barbell(100) show_anchors(30);

Figure 146

Now all of the anchors in the middle are all rooted to the cylinder. Another way to do the same thing is to use a function literal for override. It will be called with the anchor as its argument and needs to return undef to just use the default, or a [position, direction, spin] triple to override the default. As before, you can omit values to keep their default. Here is the same example using a function literal for the override:

include<BOSL2/std.scad>
module cubic_barbell(s=100, anchor=CENTER, spin=0, orient=UP) {
    override = function (anchor) 
          anchor.x!=0 || anchor==CTR ? undef  // Keep these
        : [s/8*unit(anchor)];
    attachable(anchor,spin,orient, size=[s*3,s,s],override=override) {
        union() {
            xcopies(2*s) cube(s, center=true);
            xcyl(h=2*s, d=s/4);
        }
        children();
    }
}
cubic_barbell(100) show_anchors(30);

Figure 147

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